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Convert Entities

Projects model edges and faces onto the sketch plane as sketch geometry that follows the model.

Sketch tab > Convert Entities (on the split button with Offset Entities and Mirror Entities), or Convert Entities in the Model Edges section of the sketch's page.

The Convert Entities page with a face selected on a part, its edges highlighted, and the edge count shown under Select chain.

Converting Edges

  1. In a sketch, select model edges or faces. You can also select them after the page opens.
  2. Click Convert Entities.
  3. Turn on Select chain to add the tangent chain of each selected edge.
  4. Click OK or press Enter.

The status bar reports how many edges were converted. Edges already in the sketch are not added again.

Entities to Convert

Entities
The model edges to convert, and faces, which convert all their edges. Select an item again to remove it.
Select chain
Adds every edge tangent to each selected edge, end to end. Off by default.

Under the box, the page shows how many edges will be converted.

The Converted Geometry

Model edge Sketch geometry
Line Line
Circle or arc facing the sketch plane Circle or arc
Any other curve (a spline, a tilted circle) Spline through points on it, within 0.001 mm
Edge seen end on Nothing

Edges joined end to end share their end points.

Converted geometry has an On Edge relation: every rebuild places it again where its edge now is. A face or chain converted as a whole is followed edge by edge, so edges the face gains later (more teeth, a hole added) are converted too, and edges it loses take their geometry with them. Geometry you delete stays deleted.

Edges known only by their display shape, with no exact model, come in as fixed lines.

Dangling Geometry

When the face or edge is no longer in the model, for example after its feature is deleted, the converted geometry is dangling. It stays where it was and is not part of profiles. Selected, it shows its On Edge relation marked dangling under Existing Relations. It follows its edges again once they are back.

To keep converted geometry where it is without following the model, select it and delete the On Edge relation under Existing Relations.

See Also