Skip to content

Reference Plane

Creates a plane from up to three references, each with a relation to the plane.

Features tab > Reference Plane, or Insert > Reference Geometry > Plane.

The Plane page beside a part with an offset plane.

Creating a Reference Plane

  1. Select up to three references: faces, planes, edges, sketch lines, points or cylindrical faces. You can also select them after the page opens.
  2. Click Reference Plane.
  3. Check the relation of each reference, and set its Distance or Angle. The preview updates as you type.
  4. When the page shows Fully Defined, click OK or press Enter.

Each selection goes into the next empty reference box and takes the usual relation for what is selected with it:

Selected Plane
A face or plane Offset from it
Two faces or planes Mid plane between them
A face or plane, then a point Parallel to it, through the point
A face or plane, then a line Perpendicular to it, through the line
A line or curve Perpendicular to it, at its end nearest where it was selected
A line or curve, then a point Perpendicular to it, through the point
A cylindrical face, then a point Tangent to it, through the point
Two lines Through both
Three points Through the three points

Planes offset from a face, midway between two faces, tangent to a cylinder through a point, and at an angle about an edge.

The status at the top of the page shows Fully Defined, Under Defined or Over Defined.

First Reference

Second Reference and Third Reference work the same way.

First Reference
A face, plane, sketch (its plane), edge, sketch line, point, or cylindrical face. Points include model vertices, sketch points and the centers of circular edges.
Relation

The buttons below the box list the relations the reference offers, the usual one first. Click one to use it.

Reference Relations
Planar face or plane Offset distance, Parallel, Perpendicular, Coincident, Angle, Mid plane
Linear edge or sketch line Perpendicular, Coincident, Parallel
Axis Coincident, Perpendicular, Parallel
Cylindrical face Tangent, Coincident, Perpendicular, Parallel
Curved edge or sketch arc Perpendicular
Point Coincident

Coincident, Perpendicular and Parallel on a cylindrical face use its axis. Mid plane needs two references set to Mid plane. Angle needs a line set to Coincident for the plane to turn about.

The First Reference box with a planar face in it and its relation buttons below, Offset distance pressed.

Distance
The offset from the reference, in the part's units. Shown for Offset distance.
Angle
The angle to the reference, in degrees. Shown for Angle. Default 45°.
Flip offset, Flip angle, Other side
Puts the plane on the other side of the reference. Shown as Flip offset for Offset distance, Flip angle for Angle, and Other side for Tangent.

Options

Flip normal
Reverses the plane's normal.
Size to Fit
Sizes the plane around the sketch geometry on it. Drag the handles on the plane in the graphics area to size it by hand.

When a Reference Plane Fails

The page shows the reason when the references do not define a plane. Common causes:

  • Under Defined: add a reference or change a relation, for example a point to place a parallel plane.
  • Over Defined: remove a reference or change a relation.
  • Angle without a line set to Coincident to turn about.
  • Only one reference set to Mid plane.
  • Tangent on a face that is not a cylinder, or to two cylindrical faces at once.
  • A point inside the cylindrical face the plane is tangent to.

See Also