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Lofted Boss/Base and Lofted Cut

Lofts through two or more profiles, optionally along guide curves or a centerline, to add material (Lofted Boss/Base) or remove it (Lofted Cut).

Features tab > Lofted Boss/Base or Lofted Cut, or Insert > Boss/Base > Lofted… or Insert > Cut > Lofted….

The Loft page beside a lofted part.

Creating a Loft

  1. Sketch the profiles, each closed and on its own plane.
  2. Select the profile sketches in the order the loft passes through them.
  3. Click Lofted Boss/Base or Lofted Cut.
  4. Optionally select guide curves or a centerline.
  5. Click OK or press Enter.

The sketches selected become the profiles, in the order selected. You can also select them after the page opens. With no sketch selected, a sketch that is the last feature in the design tree and is not used by a feature is taken as the first profile.

Profiles

Profiles

The profiles, in order: closed profile sketches or planar faces of the model. A face's edges are taken as its profile. The first or the last profile can be a sketch holding a single point. Select a row and press Del to remove it.

Every profile must have the same number of closed profiles, and matching profiles the same number of holes. A loft to a point needs one closed profile without holes in each other profile.

The loft passes through the profiles in the order selected. Vertices are matched between profiles for minimum twist.

Guide Curves

Guides

Optional guide sketches. Each connected chain of lines, arcs and splines in a sketch is one guide; construction geometry is left out. A guide must be tangent-continuous, meet the profile of every section, and run through the profiles in order. A guide cannot be a circle; draw it as arcs.

A loft from a square to a circle with two guide curves bending its sides, the guides highlighted.

Centerline

Centerline
An optional sketch of one tangent-continuous chain of lines, arcs and splines that crosses every profile's plane, in order. The loft follows it. Where the first or last profile is a point, the centerline must pass through that point.

A sketch can be only one of a profile, a guide and the centerline.

Start/End Constraints

Start

How the loft leaves the first profile:

Option Result
None The loft leaves the profile as it falls
Normal to profile The loft leaves square to the profile

The same loft with Start and End set to None and to Normal to profile, side by side.

Start tangent length
With Normal to profile, the length of the start tangent, as a multiple of the loft's length. Default 1.
End
How the loft arrives at the last profile. The same options as Start.
End tangent length
With Normal to profile, the length of the end tangent, as a multiple of the loft's length. Default 1.

A profile that is a point cannot have a tangency.

Options

Close loft
Runs on from the last profile back to the first, forming a ring with no end faces. Needs three profiles at least, none of them a point, and None for Start and End. Guide curves and the centerline must then be closed too.

Output

Operation
Join adds the loft to the bodies it touches. Cut removes it from every body it passes through. Intersect keeps only what each body it overlaps has in common with it. New body makes it a separate body. A feature that still has its automatic name is renamed to match, for example Boss-Extrude1 to Cut-Extrude1. An Intersect feature cannot be patterned or mirrored.

When a Loft Fails

The page shows the reason. Common causes:

  • Fewer than two profiles, or a profile sketch selected twice.
  • The profiles have different numbers of closed profiles or holes.
  • A guide curve or the centerline has a sharp corner, misses a profile, or crosses the profiles out of order.
  • The loft passes through itself because it twists too far. Match the profiles' corners or add a profile.

A Lofted Cut that misses the model still builds, with a warning that it does not intersect the model.

See Also