Skip to content

Revolved Boss/Base and Revolved Cut

Revolves a sketch profile about an axis to add material (Revolved Boss/Base) or remove it (Revolved Cut).

Features tab > Revolved Boss/Base or Revolved Cut, or Insert > Boss/Base > Revolve… or Insert > Cut > Revolve…. Right-click a sketch > Revolve for a boss.

The Revolve page beside a revolved part.

Creating a Revolve

  1. Sketch the closed profile and a centerline, or select a sketch that has them.
  2. Click Revolved Boss/Base or Revolved Cut. With no sketch selected, a new sketch starts; the page opens when you exit it.
  3. Select the axis, or leave Axis empty to use the sketch's first centerline.
  4. Set the Angle.
  5. Click OK or press Enter.

With no sketch selected, a sketch that is the last feature in the design tree and is not used by a feature is taken as the profile. Clicking the command while editing a sketch exits the sketch and opens the page.

Output

Operation
Join adds the revolve to the bodies it touches. Cut removes it from every body it passes through. Intersect keeps only what each body it overlaps has in common with it. New body makes it a separate body. A feature that still has its automatic name is renamed to match, for example Boss-Extrude1 to Cut-Extrude1. An Intersect feature cannot be patterned or mirrored.

Sketch

Sketch
The profile sketch. It must hold at least one closed profile.
Regions
The closed areas of the sketch to revolve. It starts with every area the sketch's closed profiles cover. Select inside an area to add it, and again to remove it.

Axis of Revolution

Axis

The axis to revolve about. Select one of:

  • a centerline or line in the profile's sketch. A solid line can be a side of the profile that lies on the axis.
  • a linear edge.
  • a cylindrical or conical face, or a circular edge, for its axis (right-click > Select Axis).
  • X axis, Y axis or Z axis.

An axis from the model must lie in the sketch's plane. Left empty, the sketch's first centerline is used. The text under the buttons shows which axis is used.

The profile must stay on one side of the axis.

Direction 1

The list at the top sets how far the revolve turns. The arrow button beside it is Reverse direction.

Option Extent
Blind Through the Angle
Up To Vertex Round to the vertex or sketch point in Vertex
Up To Surface Round until it reaches the face or plane in Up to
Offset From Surface As Up To Surface, stopped the Offset short of it (or past it)
Up To Body Round until it reaches the body in Up to
Mid Plane Half the Angle each side of the sketch plane
Angle
The angle to revolve through, in degrees. Default 360°. Values above 360° are taken as 360°. Accepts an equation or a variable name. Blind and Mid Plane only; a Mid Plane revolve turns less than a whole turn.
Reverse direction
Revolves the other way about the axis.
Up to, Tangent faces, Offset
As for an extrude's Up To Surface and Offset From Surface. The offset is a surface parallel to the one selected; there is no Translate surface.

When a Revolve Fails

The page shows the reason. Common causes:

  • The sketch has no closed profile.
  • No axis is selected and the sketch has no centerline.
  • The profile crosses the axis of revolution.
  • An axis from the model does not lie in the sketch's plane.

A Revolved Cut that misses the model still builds, with a warning that it does not intersect the model.

See Also