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3D Sketch

Sketches points, lines and splines anywhere in the part, not on a plane: a path for a sweep or a tube, or the layout of a frame.

Sketch tab > 3D Sketch (on the split button with Sketch). Select a 3D sketch first to edit it, or double-click it in the design tree.

img/sketch/3d-sketch-page.png

The 3D Sketch page beside a 3D sketch of lines with bends, its work plane shown at the last point.

Drawing

While a 3D sketch is open, the Sketch tab holds its commands: Exit 3D Sketch, Dimension, Line (L), Spline (S), Point (P) and Construction Geometry. Press Esc to go back to selecting. The 3D Sketch page holds the work plane, the bend radius, and the relations of the selection.

  1. Click Line, Spline or Point.
  2. Click to place points. Each point is placed on the work plane through the last point, shown as a blue square with its two axes.
  3. End a line chain or a spline: double-click, or press Enter or Esc. A spline needs two points.
  4. Click OK or press Enter to close the sketch.
Work plane
The plane points are placed on: XY, YZ or ZX, through the last point placed or selected. Press Tab to turn it to the next one. Seen edge-on, points are placed on the plane facing you instead.

Points snap to the 3D sketch's own points, to model vertices, to the centers of circular edges, and to the points of 2D sketches. A point snapped to the model is drawn green and stays on that vertex, center or sketch point when the model changes.

A line drawn within 3° of the X, Y or Z axis is held along it (an Along relation).

Bend radius
Bends the corners where two lines meet to this radius when the sketch is a sweep path. Leave it blank for sharp corners. Splines are not bent.

Moving Points

With Select, drag a free point to move it on the work plane through it. Select a single free point to show its triad: drag the red, green or blue arrow to move the point along X, Y or Z. The relations and dimensions hold as it moves. Points snapped to the model and fixed points do not move.

Relations and Dimensions

Select sketch points and entities (Ctrl + click for more), then click a button under Add Relations. Only the relations that apply to the selection are shown.

Selection Relations
A line, or a spline's end point Along X, Along Y, Along Z
A line or a spline's end point, and a face, edge or plane Along Selected Direction: a cylindrical face's or circular edge's axis, a straight edge, a planar face's or plane's normal
Two lines Parallel, Perpendicular, Dimension (the angle)
Two points Merge Points, Dimension (the distance)
A point and a line On Line
Points, and a planar face or plane On Plane
A spline's end point and a line Tangent: the spline leaves along the line
A line Dimension (its length)

Ctrl + click a face, edge or plane in the graphics area to add it to the selection for Along Selected Direction or On Plane. A spline leaving along a cylindrical face's axis runs straight out of a hole or a fitting.

Fix holds selected points where they are; Free lets them move again. Construction Geometry keeps the selected entities out of sweep paths. Delete removes the selection.

Under Relations, the relations of the selection (all of them, with nothing selected) are listed. Type a dimension's value or an equation in its field. Click the delete button beside a relation to remove it.

Status

As in a 2D sketch: blue points and entities can still move, black ones are fully defined, red means the sketch is over defined. The design tree shows (-) before an under-defined 3D sketch and (+) before an over-defined one.

See Also