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Move Face

Offsets faces by a distance, or moves them along a direction. The faces around them are extended or trimmed to meet them again. Works on any body, including imported STEP bodies that have no features to edit.

Features tab > Shell drop-down > Move Face.

Moving Faces

  1. Select the faces to move in the graphics area. You can also select them after the page opens.
  2. Click Move Face.
  3. Choose the Type: Offset or Translate. For Translate, select the Direction.
  4. Set the Distance. The preview updates as you type.
  5. Click OK or press Enter.

With Offset, a planar face moves along its normal. A cylindrical, conical, spherical or toroidal face keeps its axis and its radius changes. With Translate, the faces move along the direction without changing shape: a hole or boss moves across its face. Selecting one half of a hole moves the whole hole. The faces keep their names, so features that refer to them still do.

Fillets and chamfers next to a moved face are kept: they are removed, the face is moved, and the edges are filleted again at the same radius or chamfered again at the same distances, measured on the same faces. Fillets and chamfers made in SpryCAD keep their names.

The faces around the moved ones must still meet them. A move fails where a face would vanish or turn inside out, or a hole would run past the edge of its face.

Parameters

Type
Offset moves each face along its own normal. Translate moves all the faces the same way, along the direction.
Distance
How far the faces move. With Offset, outward from the part (adding material) by default, so a hole gets smaller.
Reverse direction
Moves the faces into the part (removing material) with Offset, or the opposite way along the direction with Translate.

Direction

Shown for Translate.

Direction
A linear edge, a planar face (its normal), a plane, the axis of a cylindrical face, or the X axis, Y axis or Z axis button.

Faces to Move

Faces
The faces to move. Select a row and press Del to remove it.

See Also