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Tables

Adds a Bill of Materials table for an assembly view, or a hole table for a part view, to the sheet. Both are made from the model each time the sheet is drawn, so they follow it as it changes.

Annotation tab > BOM Table or Hole Table (on the Table split button).

A new table is placed in the upper right corner of the sheet's border, under the revision table and any table already there. Drag it where it goes. To delete a table, select it and press Del. Tables have no page in the property panel.

BOM Table

Lists the assembly's top-level Bill of Materials: one row for each part or sub-assembly, instances of the same one sharing a row. Suppressed components are left out. See Bill of Materials.

  1. Select a view of an assembly. Without a selection, the table is for the sheet's first assembly view.
  2. Click BOM Table.

img/drawings/tables-bom.png

A BOM table on a sheet, with balloons on the assembly view numbered as its ITEM column.

Column Content
ITEM The item number. Balloons show the same numbers.
PART NUMBER The part number, or the file name where it has none
DESCRIPTION The description
QTY How many in the assembly

Text too long for its column is cut short with an ellipsis.

A new drawing of an assembly comes with a BOM table for its isometric view.

Hole Table

Lists the holes of the Hole features a view looks down, with their positions and sizes.

  1. Select a view of a part that looks along the axes of its holes, such as the view of the face they are drilled in. Without a selection, the table is for the first view on the sheet that looks down a Hole feature's holes.
  2. Click Hole Table.

img/drawings/tables-hole.png

A hole table beside a part view, the holes tagged A1, A2, B1 and the 0,0 corner marked at the view's lower left.

Each Hole feature gets a letter, A, B, C and so on, in the order of the part's features, and each of its holes a number after it: A1, A2, B1. The tags are written beside the holes in the view.

Column Content
TAG The hole's tag
X LOC The distance across from the corner marked 0,0, in the drawing's units
Y LOC The distance up from that corner
SIZE The hole's callout, as Hole Callout gives it, without the count

The 0,0 corner is the lower left corner of the view's outline, marked on the view. Distances are true model sizes, not scaled by the view's scale.

Only Hole features whose sketch faces the view are listed. When no view on the sheet looks down a Hole feature's holes, the status bar says so and no table is added.