Recognize Features¶
Finds the holes, fillets and chamfers on an imported body and makes them into features, so their sizes can be changed. The rest of the imported body stays as it is.
Right-click the Imported feature in the design tree > Recognize Features.
Recognizing Features¶
- Right-click the Imported feature and click Recognize Features. SpryCAD lists the fillets by radius, the chamfers by distance, with how many edges each has, and the holes by shape and size, with how many there are.
- Clear the ones to leave on the body.
- Click OK or press Enter.
The features go in a folder named Recognized Features, after the Imported feature:
- a Delete Face feature that takes the hole, fillet and chamfer faces off, leaving the faces whole and the edges sharp
- a Hole feature for each hole size on a face, on a sketch with a point at each hole's center
- a Fillet feature for each radius, and a Chamfer feature for each pair of distances, on those edges
Edit a Hole, Fillet or Chamfer feature to change its size, or suppress it to leave the face whole or the edges sharp. Move a point in a hole's sketch to move that hole.
Each one is checked: made again, it must give the same part. One that does not stays on the body, and the status bar names it.
What It Finds¶
- Holes
- Round holes into a flat face, square to it: simple, counterbored or countersunk, through the part or blind with a flat bottom or a 118° drill point. A cone round a hole's rim is a countersink when it reaches half the hole's radius out from the wall or more, and a chamfer when it is narrower.
- Fillets
- Round faces of constant radius, tangent to the faces on both sides, with their chains and the corner patches where three fillets meet.
- Chamfers
- Flat or conical faces between two faces, at 10 to 80 degrees to each, with equal or unequal distances.
Holes into a curved face, and holes of other shapes (a counterbore and a countersink together, a drill point of another angle), stay on the body. To edit one, use Move Face. Patterns are not recognized yet.