Sketches on Drawings¶
Draws lines, arcs and other sketch geometry on a drawing with the same sketcher as a part: on the sheet at paper size, or on a view at model size, tied to the view's edges.
Sketch tab > Sketch, right-click an empty area of the sheet > Sketch on Sheet, or double-click a view.
img/drawings/sketch-on-drawing-view.png
A sketch open on a drawing view: blue lines dimensioned to the view's edges, the rest of the sheet drawn as it is around it, and the Sketch tab alone.
Sketching on the Sheet¶
- Click an empty area of the sheet, so no view is selected.
- Click Sketch on the Sketch tab, or right-click an empty area of the sheet > Sketch on Sheet.
- Draw the geometry, and add relations and dimensions.
- Click Exit Sketch.
The sketch is at paper size, its origin at the sheet's lower left corner. Dimensions read sheet lengths.
Sketching on a View¶
Double-click a view, or select it and click Sketch. If the view has a sketch already, that sketch opens.
The sketch is in the view's own coordinates, at model size: its dimensions read the model's lengths whatever the view's scale. It moves and scales with the view, and is deleted with it.
The view's edges are there to snap to and to take relations and dimensions to. Those references follow the model: when the model changes and the view is updated, the sketch geometry tied to an edge moves with it. The edges a sketch references are the view's own and are not drawn again by the sketch.
While a Sketch Is Open¶
- The Sketch tab is shown alone. It has the same tools as in a part, except 3D Sketch. See Sketch.
- The sheet stays where it is, drawn as it is around the sketch. Its lines are there to snap and dimension to: continuous lines as lines, hidden, center and phantom lines as construction lines. Text is left out.
- The sketch's own geometry is blue.
- Clicking a sketch tool, such as Line, when no sketch is open starts one the same way as Sketch, with that tool active.
Exiting the Sketch¶
- Exit Sketch
- Keeps the sketch with the drawing as one undo step. Click it on the Sketch tab or in the confirmation corner, or click Sketch again. The Sketch tab is replaced by the tab shown before. A new sketch with nothing in it is discarded.
- Discard Changes
- Leaves the sketch as it was. See Exiting a Sketch.
A kept sketch is drawn on the sheet, and in exported and printed sheets, in black lines, with its construction
geometry as chain lines. Its dimensions and relations are the sketcher's and are not drawn. A new sketch is named
Sheet Sketch1, Sheet Sketch2 and so on, or after its view, such as Drawing View1 Sketch, and goes on the current
layer. See Layers.
Closed areas of a sheet's sketches can be hatched or filled with Area Hatch on the Annotation tab.
Editing and Deleting a Sketch¶
Each sketch is a row in the design tree under its sheet, followed by the view it is on, if any.
To edit a sketch:
- Double-click it on the sheet or in the design tree.
- Right-click its row in the design tree > Edit Sketch.
- Select it and click Sketch.
To delete a sketch, right-click its row in the design tree > Delete, or select it and press Del. Deleting a view deletes the sketches on it, and deleting a sheet deletes all of its sketches.
Missing References¶
When an edge a sketch references is gone from the model, the sketch's row in the design tree shows how many
references are missing, such as (2 missing references), in red. The sketch's geometry stays where it was.
Edit the sketch: the missing references are shown in red, and the status bar says how many. Delete them, and dimension or relate the geometry to the view's edges again.
If areas a sketch hatched are no longer closed, its row says how many hatches are not drawn. Close the areas again, or hatch them again with Area Hatch.
See Also¶
- Sketch
- Layers
- Sheet Format: the format's lines are a sketch too, opened with Linework
- Sheets