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View Properties

Each view on a sheet has its own page and shortcut menu, to set how it shows its model: display style, tangent edges, scale, center marks and the edges it leaves out.

Click a view on the sheet, or its row in the design tree, to select it and open its page. Right-click it for its shortcut menu.

img/drawings/view-properties-page.png

A selected front view and its page, with Display Style, Scale and Marks open.

The View's Page

The page has the view's name as its title, such as Drawing View1. Every change shows on the sheet as it is made. OK keeps the changes as one undo step, and Cancel puts the view back as it was. Selecting something else keeps the changes.

A section, detail, cropped or broken-out view's page starts with its own group (Section, Detail, Crop or Broken-out Section), described in Section View, Detail View and Break and Crop. The groups below follow.

Edges

Says how many edges of the view are hidden, and how many hidden edges are shown, one at a time with Hide/Show Edges (see Hiding and Showing Edges).

Show All Edges
Shown when edges are hidden: shows them all again.
Stop Showing Hidden Edges
Shown when hidden edges are shown one at a time: leaves them all out again.

Show Hidden Edges

Shown for a view drawn with hidden lines removed, or shaded. The checked features of a part, or components of an assembly, have their hidden edges shown dashed. A part lists its features that make faces, in the design tree's order; an assembly its top-level components.

Alternate Positions

Shown for a view of an assembly that has other configurations. The checked configurations are shown over the view in phantom lines.

Label

Shown for a section, detail or auxiliary view.

Letter
The view's letter, as in SECTION A-A, DETAIL B and VIEW C, and on its parent. Typed letters are made uppercase.

Display Style

How the view shows its model:

Option Shows
Wireframe Every edge, solid
Hidden Lines Visible Visible edges, and hidden edges dashed
Hidden Lines Removed Visible edges only (default)
Shaded With Edges Shaded faces with the visible edges over them
Shaded Shaded faces alone

A section view offers the first three only. Changing a view's style also changes the views projected from it that showed the same style, except sections.

Tangent edges
Draws the edges where faces meet tangentially. On by default. Applies to the view and every view projected or cut from it.
Cosmetic threads
Draws cosmetic threads: a thread's diameter as a thin line and its end. On by default. Applies to the view and every view projected or cut from it. Not shown for a detail view, which draws no threads.
Rotation (°)
Turns the view on the sheet, counterclockwise. Shown for a model, detail or auxiliary view; a projected view stays as its parent is.

Scale

Shown for a model, detail or section view. Projected and auxiliary views always have their parent's scale.

Scale

The view's own scale, or the one it takes by default:

View Default
Model view Sheet's, the sheet's scale
Section view Parent's, its parent's scale
Detail view Twice its parent's

The other options are 1:1, 1:2, 1:5, 1:10, 1:20, 2:1, 5:1 and 10:1. For any other scale, right-click the view > Scale….

Marks

Center marks
A center mark on each whole circle. On by default.
Centerlines
A centerline down each cylinder seen from the side. On by default.
Restore Deleted Marks
Shown when center marks or centerlines of the view have been deleted: brings them back. The button says how many.
Label
Shown for a section, detail or auxiliary view: draws its label under it. Deleting the label on the sheet clears this.

The View's Shortcut Menu

Right-click a view on the sheet, or its row in the design tree:

Item Does
Projected View > Right, Left, Above, Below Adds a view projected from it (see Projected View)
Display Style > a style Sets its display style, as on its page
Tangent Edges Visible Turns tangent edges on or off, for it and the views projected or cut from it
Hide Edge Hides the edge under the pointer. Shown when one is
Show All Edges Shows the edges hidden on it again. Shown when some are, with how many
Center Marks Turns its center marks on or off
Centerlines Turns its centerlines on or off
Remove Break Restores a broken view (see Break). Shown when it is broken
Scale… Asks for its scale, typed as 1:2 or 2:1. Leave it empty for the sheet's scale, or for a detail, twice its parent's. For model and detail views
Delete Deletes it (see Deleting Views)

Hiding and Showing Edges

View Layout tab > Hide/Show Edges.

Hides edges of views one at a time, or shows hidden edges one at a time in a view that leaves them out.

  1. Click Hide/Show Edges. Edges the views leave out, hidden edges and edges hidden earlier, show faint.
  2. Select an edge to hide it, or a faint edge to show it.
  3. Select more edges. Press Esc when done.

Each click is one undo step. A hidden edge stays hidden as the model changes. To show them all again, use Show All Edges on the view's page or shortcut menu.

img/drawings/view-properties-hide-edges.png

Hide/Show Edges on: a view with two edges hidden, shown faint, and its hidden edges faint and dashed.

Moving Views

Drag a view to move it. The views projected, cut or detailed from it move with it, as one undo step.

A projected view, or a section cut up or across its parent, stays in line with its parent: dragged on its own, it moves only along that line. Model, detail and auxiliary views, and angled sections, move freely. Dragging a view's label moves the view.

Deleting Views

Select a view and press Del, or right-click it > Delete. The views projected, cut or detailed from it are deleted with it, and so are the annotations and sketches on them.

Pressing Del with part of a view selected removes only that part:

Selected Removed
A center mark or centerline That mark. Restore Deleted Marks brings it back
A section, detail or auxiliary view's label The label. Select Label under Marks to show it again
A break's break lines The break

Sketching on a View

Double-click a view to open a sketch on it, which moves and scales with the view. See Sketches on Drawings.

Updating Views

A drawing's views follow the saved files of their models: when a part or assembly the drawing shows is saved, its views are updated.

View Layout tab > Update Views, or right-click the drawing's row at the top of the design tree > Update Views, loads every model again and updates the views. If a part the drawing shows is pinned to a version older than its latest release, a dialog offers to update the views to the latest revision: click Update to the new revision, or Keep the one shown.

A view shows Loading… while its model loads, and Updating… around it while it is projected again.

Views in the Design Tree

Each view has a row under its sheet, with its name and what it is: its direction, Projected, Section A-A, Detail B or View C. Hover over a row for its model's file.

Pinned
When the drawing is released, the views of its parts are pinned to the versions shown, and the row's tooltip says pinned to revision and the revision. Pinned views show that version of the part, not later ones. See Revisions for releasing a drawing and Follow Latest.
Missing model
A view whose model could not be loaded has a red row, its tooltip saying why, and is shown as last saved.

See Also