View Properties¶
Each view on a sheet has its own page and shortcut menu, to set how it shows its model: display style, tangent edges, scale, center marks and the edges it leaves out.
Click a view on the sheet, or its row in the design tree, to select it and open its page. Right-click it for its shortcut menu.
img/drawings/view-properties-page.png
A selected front view and its page, with Display Style, Scale and Marks open.
The View's Page¶
The page has the view's name as its title, such as Drawing View1. Every change shows on the sheet as it is made. OK keeps the changes as one undo step, and Cancel puts the view back as it was. Selecting something else keeps the changes.
A section, detail, cropped or broken-out view's page starts with its own group (Section, Detail, Crop or Broken-out Section), described in Section View, Detail View and Break and Crop. The groups below follow.
Edges¶
Says how many edges of the view are hidden, and how many hidden edges are shown, one at a time with Hide/Show Edges (see Hiding and Showing Edges).
- Show All Edges
- Shown when edges are hidden: shows them all again.
- Stop Showing Hidden Edges
- Shown when hidden edges are shown one at a time: leaves them all out again.
Show Hidden Edges¶
Shown for a view drawn with hidden lines removed, or shaded. The checked features of a part, or components of an assembly, have their hidden edges shown dashed. A part lists its features that make faces, in the design tree's order; an assembly its top-level components.
Alternate Positions¶
Shown for a view of an assembly that has other configurations. The checked configurations are shown over the view in phantom lines.
Label¶
Shown for a section, detail or auxiliary view.
- Letter
- The view's letter, as in SECTION A-A, DETAIL B and VIEW C, and on its parent. Typed letters are made uppercase.
Display Style¶
How the view shows its model:
| Option | Shows |
|---|---|
| Wireframe | Every edge, solid |
| Hidden Lines Visible | Visible edges, and hidden edges dashed |
| Hidden Lines Removed | Visible edges only (default) |
| Shaded With Edges | Shaded faces with the visible edges over them |
| Shaded | Shaded faces alone |
A section view offers the first three only. Changing a view's style also changes the views projected from it that showed the same style, except sections.
- Tangent edges
- Draws the edges where faces meet tangentially. On by default. Applies to the view and every view projected or cut from it.
- Cosmetic threads
- Draws cosmetic threads: a thread's diameter as a thin line and its end. On by default. Applies to the view and every view projected or cut from it. Not shown for a detail view, which draws no threads.
- Rotation (°)
- Turns the view on the sheet, counterclockwise. Shown for a model, detail or auxiliary view; a projected view stays as its parent is.
Scale¶
Shown for a model, detail or section view. Projected and auxiliary views always have their parent's scale.
- Scale
-
The view's own scale, or the one it takes by default:
View Default Model view Sheet's, the sheet's scale Section view Parent's, its parent's scale Detail view Twice its parent's The other options are 1:1, 1:2, 1:5, 1:10, 1:20, 2:1, 5:1 and 10:1. For any other scale, right-click the view > Scale….
Marks¶
- Center marks
- A center mark on each whole circle. On by default.
- Centerlines
- A centerline down each cylinder seen from the side. On by default.
- Restore Deleted Marks
- Shown when center marks or centerlines of the view have been deleted: brings them back. The button says how many.
- Label
- Shown for a section, detail or auxiliary view: draws its label under it. Deleting the label on the sheet clears this.
The View's Shortcut Menu¶
Right-click a view on the sheet, or its row in the design tree:
| Item | Does |
|---|---|
| Projected View > Right, Left, Above, Below | Adds a view projected from it (see Projected View) |
| Display Style > a style | Sets its display style, as on its page |
| Tangent Edges Visible | Turns tangent edges on or off, for it and the views projected or cut from it |
| Hide Edge | Hides the edge under the pointer. Shown when one is |
| Show All Edges | Shows the edges hidden on it again. Shown when some are, with how many |
| Center Marks | Turns its center marks on or off |
| Centerlines | Turns its centerlines on or off |
| Remove Break | Restores a broken view (see Break). Shown when it is broken |
| Scale… | Asks for its scale, typed as 1:2 or 2:1. Leave it empty for the sheet's scale, or for a detail, twice its parent's. For model and detail views |
| Delete | Deletes it (see Deleting Views) |
Hiding and Showing Edges¶
View Layout tab > Hide/Show Edges.
Hides edges of views one at a time, or shows hidden edges one at a time in a view that leaves them out.
- Click Hide/Show Edges. Edges the views leave out, hidden edges and edges hidden earlier, show faint.
- Select an edge to hide it, or a faint edge to show it.
- Select more edges. Press Esc when done.
Each click is one undo step. A hidden edge stays hidden as the model changes. To show them all again, use Show All Edges on the view's page or shortcut menu.
img/drawings/view-properties-hide-edges.png
Hide/Show Edges on: a view with two edges hidden, shown faint, and its hidden edges faint and dashed.
Moving Views¶
Drag a view to move it. The views projected, cut or detailed from it move with it, as one undo step.
A projected view, or a section cut up or across its parent, stays in line with its parent: dragged on its own, it moves only along that line. Model, detail and auxiliary views, and angled sections, move freely. Dragging a view's label moves the view.
Deleting Views¶
Select a view and press Del, or right-click it > Delete. The views projected, cut or detailed from it are deleted with it, and so are the annotations and sketches on them.
Pressing Del with part of a view selected removes only that part:
| Selected | Removed |
|---|---|
| A center mark or centerline | That mark. Restore Deleted Marks brings it back |
| A section, detail or auxiliary view's label | The label. Select Label under Marks to show it again |
| A break's break lines | The break |
Sketching on a View¶
Double-click a view to open a sketch on it, which moves and scales with the view. See Sketches on Drawings.
Updating Views¶
A drawing's views follow the saved files of their models: when a part or assembly the drawing shows is saved, its views are updated.
View Layout tab > Update Views, or right-click the drawing's row at the top of the design tree > Update Views, loads every model again and updates the views. If a part the drawing shows is pinned to a version older than its latest release, a dialog offers to update the views to the latest revision: click Update to the new revision, or Keep the one shown.
A view shows Loading… while its model loads, and Updating… around it while it is projected again.
Views in the Design Tree¶
Each view has a row under its sheet, with its name and what it is: its direction, Projected, Section A-A, Detail B or View C. Hover over a row for its model's file.
- Pinned
- When the drawing is released, the views of its parts are pinned to the versions shown, and the row's tooltip says pinned to revision and the revision. Pinned views show that version of the part, not later ones. See Revisions for releasing a drawing and Follow Latest.
- Missing model
- A view whose model could not be loaded has a red row, its tooltip saying why, and is shown as last saved.