Hole¶
Creates simple, counterbore or countersink holes at points sketched on a planar face or plane, sized by hand, from the clearance hole standards in the libraries, or by a standard drill size.
Features tab > Hole, or right-click a planar face or plane > Hole. Parts only.

Creating a Hole¶
- Select the planar face or plane for the holes, then click Hole. A points-only sketch opens on it.
- Click on the face to place hole centers. Locate them with Dimension.
- Click OK. The Hole Specification page opens.
- Set the hole type, the Standard, Type, Size and Fit, and the end condition. The preview updates as you change them.
- Click OK or press Enter.
To place the holes, you can also select a sketch, or a point or curve of one, before clicking Hole: the holes go at its points, or at its circles' centers when it has no points. With nothing selected, the last feature is used when it is a sketch that no feature uses yet. With nothing usable selected, the Hole Position page opens.
Canceling the Hole Specification page of a new hole also removes the position sketch the command created.
Hole Position¶
Opens when no face, plane or sketch was selected. Every sketch in the part is shown while it is open.
- Face
- The planar face or plane on which to place the holes, or a sketch whose points or circles' centers locate them. Selecting a face or plane opens the points-only sketch on it; selecting a sketch goes straight to the Hole Specification page.
Hole Positions¶
The points-only sketch where the hole centers are placed. Only the Point, Select and Dimension tools are available. Each point that is not construction geometry is a hole center. Click OK to go on to the Hole Specification page; a sketch closed with no points is discarded.
Hole Type¶
The type, chosen from a row of buttons:
| Option | Hole |
|---|---|
| Simple | Drilled straight, through or to a depth |
| Counterbore | A socket head screw's head sunk below the face |
| Countersink | A flat head screw's head flush with the face |

- Library type
-
Built-in for the hole type buttons, or a hole type from the libraries in their place: a profile with its own sizes, or one sized by a thread. Built in:
Option Hole Pipe tap Taper reamed at 1:16 from the thread's minor diameter at the face, the tap drill below. NPT, NPTF and Rc threads. Bottoming tap The tap drill with its point, threaded to 1.5 pitches above the drill depth. Any straight thread. A type sized by a thread shows the Thread, Size and Class pickers in Hole Specifications.
- Standard
- The standards the hole's sizes come from: ANSI Inch, ISO, and any other group the libraries have tables for. It starts on the part's standard (ANSI Inch for an inch part, ISO for a metric one, or the one set in Tools > Options > Document Properties > Standards), and can be changed for one hole whatever the part's units: a metric drill in an inch part is Standard ISO, Type Drill sizes. It also chooses the thread tables of a tapped hole and the library types listed.
- Type
-
What the hole is sized for, from the Standard's tables:
Option Hole Shown for Fractional, Number, Letter drill sizes Inch drills (1/64 to 2, #80 to #1, A to Z; ASME B94.11M) Simple holes, inch standards Drill sizes Metric drills (0.5 to 32 mm; ISO 235) Simple holes, metric standards Screw clearance A screw size's clearance (ISO 273, ASME B18.2.8), the same for every screw type. Insert Fastener picks the screw Simple holes Socket head cap screw, Flat head screw… The screw's clearance and its head's counterbore or countersink Counterbores, countersinks Custom entry No table: type the diameters Every hole type The list holds the tables the libraries offer, so it can differ from the built-in ones above. Not shown for a tapped hole, which is sized by its Thread.
Hole Specifications¶
The page is laid out as in SolidWorks: the type, size and depth set on most holes at the top, the options, profile and positions in collapsible sections below.
- Size
- The drill size (#7, F, 27/64, 6.8) or screw size, from the Type's table. Not shown for Custom entry.
- Fit
- The clearance column of the table: Close, Normal or Loose. Shown only when a clearance table is set. Normal by default.
- Thread, Size, Class
- A tapped hole's thread table, thread size and class (2B, 3B). The hole's diameter is the size's tap drill.
A sized hole shows its diameters in one line below the pickers: Diameter 0.281 in; counterbore 0.438 in, 0.25 in
deep. The part keeps a copy of the library rows it uses, so it rebuilds the same without the libraries. Where a
companion table has no row for the size, the status bar says so and the values stay as they were, to be typed.
- Override sizes
- Shows the diameter fields with the table's values, to type over them. The typed values are kept over the table's; Use Library Values puts the table's back.
The diameter fields are shown with Override sizes or Custom entry:
- Diameter
- The hole diameter, in the part's units.
- C'bore dia., C'bore depth
- The counterbore diameter, larger than the hole, and its depth from the face. Counterbore holes only.
- C'sink dia., C'sink angle
- The countersink diameter at the face, larger than the hole, and its included angle. Countersink holes only.
End Condition¶
How deep the hole goes, chosen from a row of buttons:
| Option | Depth |
|---|---|
| Blind | To the Depth |
| Through All | Through the whole part |
| Up To Next | Through the first material it meets |
| Up To Surface | To the plane or face in Up to |
- Depth
- The depth from the sketch plane. Blind only.
- Up to
- The plane or face the hole stops at, each hole where its axis meets it, the bottom square to the axis. A face of a cylinder, cone, sphere or torus is extended where an axis misses it. Up To Surface only.
- Drill point
- Ends the hole in a drill point. Blind only. On by default.
- Point angle
- The drill point's included angle: 118° for a standard twist drill, 135° for a split point drill. Shown with Drill point.
- Depth to tip
- Measures Depth to the drill point's tip. Off by default: the depth is to the end of the full diameter (the shoulder), as ASME Y14.5 gives a hole's depth. Shown with Drill point.
The hole's callout names its drill and gives the full diameter depth, whichever way Depth is measured:
2X #7 (⌀0.201) DRILL ↧ 0.5. A point angle other than 118° is added (135° POINT), and a blind hole without a drill
point ends in FLAT BTM. A metric drill in a metric part is called out by its diameter: ⌀6.8 DRILL ↧ 12.
- Reverse direction
- Drills the other way. The hole goes into the part from the sketch plane: against the plane's normal, or along it when the whole part lies on the normal's side.
- Thread depth
- How deep a tapped hole is threaded. Blank: as deep as the hole goes, or the library type's thread depth.
Options¶
Collapsed unless one of its options is on. Hidden with a custom profile.
The optional extra countersinks each show their Diameter and Angle when turned on; an empty diameter is set a little larger than the diameter it widens.
- Near side countersink
- Where the hole meets the face, or at a counterbore's rim. Not shown for a countersink hole.
- Under head countersink
- Where the hole leaves the counterbore's floor. Counterbore holes only.
- Far side countersink
- Where the hole comes out on the far side. Through All and Up To Next only.

- Clear material above
-
Continues the hole's top diameter (its counterbore's, countersink's or its own) back out through material above the sketch plane, such as a fillet over a counterbore. On by default.

- Cosmetic thread
- Shows a tapped hole's thread as a helix on the wall. Clear it to cut the thread. View > Threads overrides the display of all threads.
Profile¶
The section revolved at each hole position: the hole type's standard profile, or the hole's own. Collapsed unless the hole has its own profile.
- Edit Profile…
- Opens the profile in the sketch editor at the first hole position: half the hole in section, its axis the vertical
through the origin. Its dimensions can use
D,Depth,CbD,CbDepth,CsDandCsAngle(the hole's values), and the part's equations. Closing the sketch returns to this page. Needs at least one hole position. - Use Standard Profile
- Discards the custom profile. Shown only with a custom profile.
Positions¶
Collapsed.
- Edit Hole Positions…
- Opens the position sketch. For a new hole, closing the sketch returns to this page; for an existing hole, the page closes without applying its changes.