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Reference Axis

Creates an axis from one or two references. Its type follows from what is selected.

Features tab > Reference Axis, or Insert > Reference Geometry > Axis.

The Axis page beside a part with an axis through a cylindrical face.

Creating a Reference Axis

  1. Select one or two references. You can also select them after the page opens.
  2. Click Reference Axis.
  3. Check the type shown under the box.
  4. Click OK or press Enter.

Selections

References
Up to two references: a linear edge, sketch line, cylindrical or conical face or circular edge (its axis), or another axis; a plane, planar face or sketch (its plane); a point (model vertex, sketch point or the center of a circular edge).

The type the references make shows under the box:

Selected Type shown Axis
One linear edge, sketch line or axis Along the line or edge Along it
One circular edge Along the line or edge Along its axis
One cylindrical or conical face Along the round face Along its axis
Two planes or planar faces Where the two planes meet Their intersection
Two points Through the two points Through both points
A point and a plane Square to the plane, through the point Normal to the plane, through the point

Axes made where two planes meet, through two points, and normal to a plane through a point.

Other combinations show Incomplete references, and no axis is created.

When a Reference Axis Fails

The page shows the reason when the references make no axis, for example two parallel planes or two points at the same place.

See Also