Revisions¶
Releasing a drawing gives it and the models it shows one revision label, such as A, together. The part views are
pinned to the versions released, so the drawing keeps showing them as the parts change, until it is released again.
Drawing tab > Release Revision and Follow Latest. Release Revision… is also on the right-click menu of the drawing's row at the top of the design tree.
Releasing a Revision¶
- Save the drawing, and update its views if a model changed.
- Click Release Revision. If the drawing has unsaved changes, click Save to save it first; only the saved drawing is released.
- Check Revision, and type a Description and Approved by.
- Click Release.
img/drawings/revisions-release.png
The Release Revision dialog with Revision B proposed, a description typed, and Save a PDF beside the drawing selected.
The release is saved in the drawing's file and in each part's at once. It is not undone with Ctrl+Z.
For each model the drawing shows:
- The version shown is released with the label, unless it is released already; then it keeps its own label.
- The version is marked as one a drawing shows, so Purge keeps it.
- A part's views are pinned to that version. An assembly's views keep showing its latest version.
The drawing's row in the design tree then shows its revision, such as (Rev A), and the tooltip of a view's row shows
the revision its part is pinned to. The title block's {Revision} field shows the drawing's revision, - until it is
released.
Release Revision Dialog¶
- Amend revision
- Shown once the drawing has a revision. Replaces the drawing's latest revision with its current version, for a fix that does not need a new revision. Revision keeps the old label, Description and Approved by are filled in with the old values, and the button reads Amend. The parts keep their releases. Only the latest revision can be amended, and only while every part is shown at a released version.
- Revision
- The label. Proposed as the next after the drawing's own revisions:
A,B, … (I, O, Q, S, X and Z are skipped), or01,02, … when the sheet format numbers revisions. A label the drawing has already is refused. - Description
- What changed, or what the revision is for. Shown in the revision table.
- Approved by
- Shown in the revision table. The author recorded is the Author name in Tools > Options > Files.
- Save a PDF beside the drawing
- Saves every sheet as
<drawing> Rev <label>.pdfin the drawing's folder. Selected by default.
Drawings of One Part¶
A drawing of one part takes the part's revision. When the part version shown is released already, as C say,
Revision is set to C, and the drawing is released as C too. To release it under another label, click
Follow Latest first, so the views show the part's latest version.
When the drawing already has that revision, a new one needs a newer version of the part shown:
- If the part has a newer version, Release Revision asks whether to Show Latest, which shows the part's latest version and saves the drawing before the dialog opens, or Amend the revision.
- If not, the dialog opens with Amend revision selected.
When Release Is Refused¶
The dialog or a message says why. A release needs:
- The drawing saved, and on Main. Releases are not made on branches.
- Every model loaded, a SpryCAD file, and not being edited by someone else.
- The views up to date. Click Update Views on the View Layout tab after a model changes.
- Parts open in other tabs saved. A part with unsaved changes would release what is saved, not what its tab shows.
Follow Latest¶
Follow Latest unpins every view, so each shows the latest version of its model. It is one undo step. The status bar says so when the views follow the latest versions already. Release a revision to pin them again.
Newer Revisions of a Part¶
When the drawing opens, or its views are updated, a part pinned to a version older than the part's latest release is reported in a Newer Revision message, such as "bracket is released as revision B; the drawing shows revision A". Click Update to B to pin the part's views to that release, or Keep A to leave them.
Revision Table¶
The sheet formats SpryCAD comes with have a revision table hanging from the upper right corner of the border. It lists each release of the drawing, oldest first, under the headings Rev., Description, Date and Approved (REV, DESCRIPTION, DATE, APPROVED in ANSI). The date is the day of the release. Text too long for its column is cut short with an ellipsis.
img/drawings/revisions-table.png
The revision table in a sheet's upper right corner with revisions A and B listed.
To hide the table, or to number revisions 01, 02 instead of lettering them, edit the sheet format's settings. See
Sheet Format.
Versions and Branches¶
Each save of a drawing is a version, as with a part. The Revisions tab on the task pane lists them, releases included, with the drawing's branches.
- Right-click a version > View This Version to see it, read-only.
- Right-click > New Branch from This… to start a branch. Switch to and Merge … into … work on the lines ending at a version.
- The branch box above the list switches between Main and the branches. Its menu has New Branch…, Merge into This Branch, Rename Branch… and Delete Branch.
When someone else saved the drawing after you opened it, Save asks whether to Merge… your changes with theirs, Save as Branch to merge later, or Overwrite their version, which keeps theirs as a branch.
A merge combines sheets, views, annotations, sketches, sheet formats and models one by one. The drawing's settings (units, title block values, drafting standard and layers) merge as a whole. Items both sides added with the same name are renamed, and the status bar lists them. Annotations and sketches on a sheet or view the merge removed are left out, and a message lists them. Save the drawing to keep the merge; Ctrl+Z undoes it.
File > Merge From… merges another copy of the drawing, such as one sent by email, into the line the drawing is on.