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Mate

Positions a component relative to another component, or to an origin plane, by relating two of their faces.

Assembly tab > Mate (on the split button with Motor). Also on the context palette of a selected component and on the assembly's mouse gesture ring (right).

The Mate page on the Standard tab with two faces in Mate Selections and Coincident selected, beside a bracket mated to a plate.

Adding Mates

  1. Click Mate.
  2. Select two faces on different components, or a face and an origin plane. The likely mate type is selected and the components move to it.
  3. Select another type in Mate Type if needed, and set its values in Options.
  4. Click OK or press Enter. The mate is added and the page stays open for the next one.
  5. Click OK with nothing selected, or Cancel, to close the page.

The component of the first selection moves onto the mate if it floats; otherwise the second one moves. Then all the mates are solved. A fixed component never moves. Each mate added is its own undo point. Cancel drops only the mate being set up; mates already added stay.

The page needs at least one component in the assembly, and cannot open while the Motor page is open.

Standard and Mechanical

Two tabs at the top of the page switch the type list between Mate Type (Standard) and Mechanical Mates (Mechanical).

Mate Selections

The two references of the mate. Each is listed as SolidWorks lists it, for example Face<Top>@Plate<1>, Axis<Bore>@Shaft<1> or Front Plane. Its tooltip says what it is: a planar face, a cylindrical face's axis and radius, or a sphere's center.

  • Selecting a face adds it. Selecting it again removes it. A third selection replaces the second.
  • Planar faces are taken as planes; cylindrical and conical faces as their axes; spherical faces as their centers. Other faces cannot be mated.
  • To mate the center of a hole or boss instead of its axis, right-click its cylindrical face and select Select Center. That takes the center of the face's circular edge at the end nearer the cursor. Select Axis takes the axis, as a click does.
  • Select an entry to show its face in the selection color and the other one paler. Hovering an entry shows its face in orange.
  • Press Del to remove the selected entry, or right-click for Delete and Clear Selections.
Front, Top, Right
Adds that origin plane of the assembly. Hovering a button shows the plane, even when the planes are hidden. The origin planes in the flyout design tree can be selected as well.
Planes of
Which assembly the plane buttons take their planes from: Assembly, or a sub-assembly. Shown only when the assembly has sub-assemblies. On a Library Feature's mates in a part, This part or the library part: each adds its own reference planes and axes to the buttons, after Front, Top, Right and Z Axis; meanwhile they are drawn in the graphics area (the library part's where it is), to click on. A plane through the middle of a library part (a latch's center) lets it be mated from there rather than from its edges.

Both references cannot be on the same component, and two origin planes cannot be mated to each other.

Mate Type

The types that cannot relate the two selections are unavailable. When the selections change, the type is chosen again: Concentric for two axes or an axis and a center, Perpendicular for an axis and a plane, and Coincident otherwise.

Type Selections Result
Coincident Two planes Coplanar, normals aligned or anti-aligned
Plane and axis The axis lies in the plane
Plane and center The center lies on the plane
Two axes Collinear
Axis and center The center lies on the axis
Two centers The centers coincide
Parallel Planes or axes Parallel normals or axes; an axis and a plane: the axis parallel to the plane
Perpendicular Planes or axes At 90°; an axis and a plane: the axis along the plane's normal
Tangent A plane and a cylinder or sphere The cylinder or sphere touches the plane, on the side it is on now
Two cylinders or spheres, or one of each Touching, outside each other or one inside the other, whichever is nearer how they lie now
Concentric Two axes, an axis and a center, or two centers On the same axis, or at the same center
Lock Any Holds the two components where they are now relative to each other
Angle Planes or axes The angle between their normals or axes

Tangent needs a radius, so it does not take conical faces, and it does not relate two planes.

Coincident with an Offset holds the references that far apart: measured from a plane along its normal, or between the axes or centers. Files that have a Distance mate open with it as such a Coincident.

Mechanical Mates

Both mechanical mates take two cylindrical (or conical) faces.

Gear
The two components turn together at a ratio, in opposite directions. Gear relates only their rotations: hold each component on its axis with other mates, such as Concentric to a shaft.
Screw
The two references stay on one axis, and turning one moves the other along it by the lead per turn. The turn and axial position at the time the mate is added are the starting point.

Options

The fields shown depend on the type. A value is applied when you press Enter or leave the field, and the components move to it. Up and Down step the value by 1 (Shift: 10, Ctrl: 0.1). A value typed without a unit takes the assembly's.

Offset
Coincident only. The distance between the references. 0 makes them touch; a negative value puts the component on the other side.
Angle
Angle only. From 0° to 180°.
Limits
Coincident and Angle. Replaces Offset or Angle with Minimum and Maximum: the distance or angle may be anywhere in that range, and a dragged component moves within it.
Ratio: first, Ratio: second
Gear only. The first component turns Ratio: second / Ratio: first times for each turn of the second. Both start as the faces' radii; enter teeth counts or pitch diameters instead. Leave a field empty to return it to the radius.
Reverse direction
Gear only. Both components turn the same way, as with an internal gear or a belt.
Lead per turn
Screw only. The axial travel for one turn.
Left hand
Screw only. A left-hand thread: the same turn moves the component the other way along the axis.
Mate alignment

Whether the second reference's normal or axis points the same way as the first's (Aligned) or the other way (Anti-aligned: faces against each other). The mate starts with the one nearer how the components lie now. Not shown for Tangent, Lock, Gear and Screw.

One Coincident mate between two plates shown twice, with Mate alignment set to Aligned and Anti-aligned.

The line below the options says Click OK (Enter) to add the mate., or shows the error described below.

Mate Errors

A mate the solver cannot satisfy, because it conflicts with other mates or with fixed components, shows Mate conflicts with existing mates or fixed components. with its error, in red. OK still adds it. To fix it, select another type or alignment, change the value, or suppress or edit the mate it conflicts with.

In the design tree, a mate that is not satisfied is shown in red, with its error in the tooltip. A collapsed Mates folder is red when any of its mates is.

A mate whose component was deleted, or whose face is gone from the part, shows missing reference and the reason. Right-click it and select Repair…: the page opens with the missing reference removed. Select the replacement, then click OK.

Mates in the Design Tree

Mates are listed in the Mates folder, each with its type's icon, its name, its value (offset, angle, limits, ratio or lead) and the two components. With more than 50 mates the folder starts collapsed and shows their count. Selecting a mate shows its two faces in the graphics area.

Right-click a mate for:

Command Result
Repair… Only for a mate with a missing reference; see above
Edit Mate… Opens the mate on the Mate page. Double-clicking the mate does the same
Rename… Renames the mate (F2). Names must be unique
Flip Alignment Switches between aligned and anti-aligned
Suppress, Unsuppress A suppressed mate is grayed and not solved
Delete Deletes the mate. Del does the same for the selected mate

The Mates folder in the design tree with one mate in red for a conflict, one suppressed and one with a missing reference.

Editing a Mate

Edit Mate… opens the page titled Edit Mate: and the mate's name, with its references, type and values. The components follow each change. OK keeps the changes, with the mate in the same place in the list. Cancel puts the mate and the components back as they were.

The mate keeps its name. If you change its type, it takes the next name of the new type, for example Coincident2 becomes Angle1.

Dragging Components

Drag a floating component in the graphics area to move it as its mates allow. It moves in the plane of the screen through the point you grabbed; where the mates stop it sliding, it turns so that point follows the cursor, and the components mated to it move with it. A gear dragged around its axis turns its mate. Shift + drag rotates the component about its center.

  • A fixed component cannot be dragged.
  • A component of a rigid sub-assembly drags the whole sub-assembly; in a flexible one, the component moves on its own (see Sub-assemblies).
  • A drag that would leave satisfied mates unsatisfied is not taken.
  • Components cannot be dragged while the exploded view is on (see Exploded View).

To drive a mechanism at a steady speed, use Motor.

See Also